Grid Motion Tutorials
Intent: Demonstrate setup and execution of moving overset grids (FUN3D Version 11.0 and higher)
This tutorial will describe how to set up and run a case with moving geometry utilizing overset meshes.
Note: the input data provided in the download files is for FUN3D Version 11.0 and higher and will not work with earlier versions
All the grid and input files may be downloaded below. Note that the grids for this case are very coarse and are intended for demonstration, rather than accurate aerodynamic analysis. The geometry consists of a wing and a store, and is one of the geometries included in SUGGAR++ training materials.
The user should be familiar with running the baseline flow solver, and preferably with running moving geometry cases that don’t require overset grids (See Time Accurate – Moving Geometry).
The process is composed of a few basic steps. The download file has a directory structure roughly aligned with these steps. This directory structure is convenient for demonstrating the process, but is not required. First, a composite mesh with the configuration in the initial position is generated from component meshes (in this case wing and store) by running SUGGAR++. The domain connectivity information (dci) for the geometry in the initial position is also computed by SUGGAR++. Next, an initial, steady-state, static geometry computation is performed. The final stage of the tutorial consists of a time-dependent, moving grid computation in which the store motion is specified as a constant downward velocity. The included README files provide step-by-step directions similar to those given on this web page.
Compilation and linking
Download (9.6Mb) and gunzip/untar the files:
Wing_Store/ README Component_Grids/ store.cogsg store.mapbc wing.cogsg wing.mapbc wing.bc store.bc T=0_Domain_Connectivity/ Input.xml_0 README Steady_State/ README RUN_IT fun3d.nml Dynamic_Specified/ moving_body.input README RUN_IT fun3d.nml
Create the composite mesh and initial domain connectivity information
In this step the component grids, located in the
are combined into a single composite VGRID set using SUGGAR++, and at the same time the domain
connectivity information is computed for the configuration in the initial t=0 position.
Below it is assumed that your suggar++ executable is called suggar++; your
executable may be named differently, depending on your compilation
platform and compilation options. It is also assumed for illustration purposes that
your SUGGAR++ executable is
located in a directory /Your/Path/To/Suggar++ The input for SUGGAR++ is provided in the
file located in the T=0_Domain_Connectivity directory.
cd Wing_Store/T=0_Domain_Connectivity ln -s ../Component_Grids/* . ln -s /Your/Path/To/Suggar++/suggar++ . (./suggar++ Input.xml_0 > suggar_output) >& suggar_error &
At this point you should have the domain connectivity file wingstore.dci, along with a VGRID file set (wingstore.cogsg, wingstore.mapbc, wingstore.bc) for the composite mesh. You may want to check to see if any orphan points resulted:
grep "orphans because" suggar_error
You may want to use the GVIZ utility code for SUGGAR++, available from Ralph Noack to view the composite mesh. GVIZ allows visualization of the composite mesh, hole points and fringe points, and can aid in debugging hole-cutting issues. However, it is beyond the scope of this FUN3D tutorial to describe the use of GVIZ.
Next, we obtain a steady-state solution for the configuration in the t=0 position.
This steady-state solution will be used as the initial solution for the dynamic simulation.
A sample run script, RUN_IT, is provided, though it may need modification for
your particular system. The run script and
fun3d.nml file are such that running FUN3D will
generate solution-visualization (TECPLOT) output from within
the flow solver.
Below, it is assumed that your FUN3D executable (nodet_mpi) is located in /Your/Path/To/Fun3d
cd ../Steady_State ln -s ../T=0_Domain_Connectivity/wingstore.cogsg . ln -s ../T=0_Domain_Connectivity/wingstore.mapbc . ln -s ../T=0_Domain_Connectivity/wingstore.bc . ln -s ../T=0_Domain_Connectivity/wingstore.dci . ln -s /Your/Path/To/Fun3d/nodet_mpi . ./RUN_IT
The—animation_freq -1—sampling_freq -1 options in the RUN_IT script generate TECPLOT output at the end of the flow solver execution. See Flow Visualization Output Directly From Flow Solver for more information. Here we have used the—sampling_freq option, together with input from the fun3d.nml file, to extract Cp data on a y=0 plane through the flow domain. The—animation_freq option, together with input from the fun3d.nml file is used to extract Cp data on the solid surfaces (wing and store surfaces). Because this is an overset mesh, the default output will contain iblank data. If you have configured FUN3D to link against TECPLOT’s tecio libraries (See Third-Party Libraries – TECPLOT), then these visualization files will be binary, and will have a .plt extension; otherwise, they will be ASCII files and have a .dat extension. TECPLOT360-2009 was used to generate the following image from the wingstore_tec_boundary.plt (or .dat) and wingstore_tec_sampling_geom1.plt (or .dat) files. Value blanking on variable iblank was used, with blanking for iblank=0.
Dynamic, moving-grid solution
The steady-state solution obtained above may be used as a starting point for the moving-mesh simulation. Not all moving-mesh simulations need be or in fact can be started from a steady state, although in this case the steady-state initial condition is reasonable. Note that for dynamic overset meshes, not only must the composite mesh be visible to the flow solver, the meshes of all component meshes (static and dynamic) must be visible as well.
cd ../Dynamic_Specified cp ../Steady_State/wingstore.flow . (note: copy, do not link) ln -s ../Component_Grids/* . (dynamic overset grids need the component grids too) ln -s ../T=0_Domain_Connectivity/wingstore.cogsg . ln -s ../T=0_Domain_Connectivity/wingstore.mapbc . ln -s ../T=0_Domain_Connectivity/wingstore.bc . ln -s ../T=0_Domain_Connectivity/wingstore.dci . (always need the initial dci data) ln -s ../T=0_Domain_Connectivity/Input.xml_0 . ln -s /Your/Path/To/Fun3d/nodet_mpi .
The motion simulation here is one in which the velocity of the store is specified to be constant, in a downward direction. The moving_body.input file provided in the download tar file is reproduced below:
&body_definitions n_moving_bodies = 1, ! number of bodies in motion body_name(1) = 'store', ! name must be in quotes n_defining_bndry(1) = 1, ! number of boundaries that define this body defining_bndry(1,1) = 4, ! index 1: boundary number index 2: body number mesh_movement(1) = 'rigid', ! 'rigid' or 'deform' motion_driver(1) = 'forced' ! motion is specified below / &forced_motion translate(1) = 1, ! translation type: 1=constant rate 2=sinusoidal translation_rate(1) = -0.2, ! translation velocity (mach) / &composite_overset_mesh input_xml_file = 'Input.xml_0' /
See Time Accurate – Moving Geometry
for descriptions of all input parameters above. However, a few comments are
warranted here. For both the steady-state and time-dependent cases, the
‘patch_lumping = “family”’ option was set in the
fun3d.nml file. Thus, to the flow solver, the store appears as a
single boundary, boundary number 2.
It is this lumped boundary numbering that must be used in the
&body_definitions namelist above. Because the compressible flow equations in FUN3D are
normalized with speed of sound, the specification of the body velocity of -0.2 is equivalent
to Mach 0.2 (downward); the freestream Mach number in this case is 0.95.
The input_xml_file is set to be the same Input.xml_0 file that was used with
SUGGAR++ to compute the initial (static) DCI data. Note that in this case,
in anticipation of running the dynamic simulation, a
was already placed in the
<body name="store"> element at set up time. The
<dynamic/> element has no impact on the static grid
solution, but does set some additional data that is needed by FUN3D to define
which volume grid points are associated with a particular moving body.
The included RUN_IT script for the moving mesh run is reproduced below.
#!/bin/sh (mpirun -np 9 -nolocal -machinefile machinefile ./nodet_mpi --temporal_err_control 0.1 --dci_on_the_fly --sampling_freq 5 --animation_freq 5 --moving_grid --overset > screen_output) >& error_output & exit
Several important points need to be made here. First, note that the command line option
--dci_on_the_fly is used trigger a computation of new domain connectivity information
at each new time step. This is necessitated by the use of
--overset in conjunction with
--moving_grid, together with the fact that dci files do not exist a priori for the store
mesh at each new position. If the dci files for each time step did already exist, then
--dci_on_the_fly would not be needed and they would simply be read in each time step.
--dci_on_the_fly is utilized, the flow solver will write out dci files for each
time step; these can be reused for repeat runs, without having to do the (relatively
expensive) calculation of the dci data each step. This is most useful in periodic motions,
where the the flow solver is first run for one period of motion with
Subsequent restarts omit
--dci_on_the_fly and instead use
--dci_period N where N is the
number of time steps in the period. Note that this example is NOT periodic, so any restarts
beyond the 50 time steps in the
fun3d.nml file need to be run with
Note also that although this example utilizes 8 processors to solve the flow equations,
the number of processors used in the mpirun command is 9. When
--dci_on_the_fly is used,
ONE extra processor is devoted to the task of computing the overset connectivity data.
Future versions of the FUN3D and SUGGAR++ are expected
to support multiple processors for the dci computation. A very important consequence
of the single processor computation of the dci data is that that processor must have
sufficient memory to hold the entire mesh on that processor. The SUGGAR++ processor is
the first processor in the machinefile list. If the dci files already exist, so that
--dci_on_the_fly is not used, the the number of processors should be set back to
equal the desired number of flow solver processors.
The command-line options—sampling_freq 5 —animation_freq 5 are used to dump out tecplot files much like was done for the steady-state case, except that now the files are generated every 5 time steps. File names contain “_timestepN” to denote which timestep they correspond to. TECPLOT360-2009 was used to generate the animation files below. All .plt (or .dat) files were read with the multiple files option, and in the “Unsteady Flow Options” panel (under the “Analyze” panel) was used to parse the zones by time. Then animation was created using the “Step by Time” option in the “Animation” panel. The first animation shows Cp, analogous to the still image created from the steady-state solution. The second animation shows the dynamic hole cutting as the mesh is moved. To make this animation the mesh was colored by the contour variable imesh. Since there are only two meshes in the composite mesh, all points are either blue (wing) or red (store). Since the mesh in this example is so coarse, the hole cuts tend to be more ragged than with finer meshes, and likewise the contours not as smooth as with finer meshes..
The command-line option—temporal_err_control 0.1 is used to terminate subiterations when the estimate of the temporal error in a time step drops 1 order of magnitude lower than the residual. It is beyond the scope of this tutorial to discuss the theory and potential benefits of this option, but is included here because it is our standard practice for time-accurate simulations. More info can be found in the Training Session materials.